Programming manual
CNC 8070
CANNED CYCLES
G86. Boring canned cycle
10.
(SOFT V02.0X)
197
10.7 G86. Boring canned cycle
Programming format in Cartesian coordinates:
G86 Z I K R
Parameter definition:
Basic operation:
1. If the spindle was previously running, it maintains the turning
direction. If it is stopped, it starts clockwise (M03).
2. Rapid movement (G0) of the longitudinal axis from the starting
plane (Zi) to the reference plane (Z).
3. Boring the hole. Movement of the longitudinal axis at work
feedrate, to the bottom of the hole programmed in "I".
4. Dwell, in seconds, if it has been programmed.
5. If "R=0" has been programmed, the spindle stops (M05).
6. Withdrawal to the starting plane (Zi) if function G98 is active or to
the reference plane (Z) if function G99 is active.
In rapid (G0) if "R=0" and at work feedrate (G01) if "R=1".
Z Reference plane.
In G90, coordinate referred to part zero.
In G91, coordinate referred to starting plane (Zi).
If not programmed, it assumes as reference plane the current
position of the tool (Z=Zi).
I Boring depth.
In G90, coordinate referred to part zero.
In G91, coordinate referred to reference plane (Z).
K Delay, in seconds, between the boring and the withdrawal
movement.
If not programmed, it assumes K0.
R Type of withdrawal: R0 rapid (G0), R1 at work feedrate (G01).
By default, R0.
To Next Page
Loading...
