Haas 96-8000 - I.D. Thread Milling Exercise

137
96-8000 Rev AC
May 2010
G & M Codes
Settings
.
Thread Milling 1.5 dia.x8TPI
Tool Path
Turn On and Off
Cutter Compensation
I.D. Thread Milling Exercise
Move away
from I.D.
Move to
I.D.
N1
N5
N2
N4
N3
Thread Milling Example
Program Example Description
%
O02300
T1 M06 (0.5 DIA 2FLT. THREAD MILL) (Thread milling 1.5 x 8 TPI)
G00 G90 G54 X0. Y0. S1910 M03 (X0. Y0. is at the center of the hole)
G43 H01 Z0.1 M08 (Z0. is at the top of the part - using .5”
thick material)
G00 Z-0.6
N1 G01 G41 D01 X0.125 F30. (Turn on Cutter Comp)
N2 G03 X0.75 Y0. R0.3125 F11.5 (Move to I.D. of bored hole)
N3 G03 I-0.75 Z-0.475 (One full revolution with Z moving up .125
N4 G03 X0.125 Y0. R0.3125 F30. (Move away from the new threads)
N5 G01 G40 X0. Y0. (Cancel Cutter Comp)
G00 Z0.1 M09
G28 G91 Y0. Z0.
M30
%
Note: Maximum cutter compensation adjustability is .175.