Haas 96-8000 - Program Code for Mirror Imaging in the X-Axis

177
96-8000 Rev AC
May 2010
G & M Codes
Settings
Correct: Incorrect:
G41 X1.0 Y1.0 G41 X1.0 Y1.0
G01 X2.0 Y2.0 G01 X2.0 Y2.0
G101 X0 G101 X0
G00 Z1.0 G00 Z1.0
G00 X1.0 G00 X2.0 Y2.0
G00 X2.0 Y2.0
G40 G40.
Mirroring only one of the X or Y axes will cause the cutter to move along the
opposite side of a cut. In addition, if mirror imaging is selected for only one axis
of a circular motion plane (G02, G03) then they are reversed, and left and right
cutter compensation commands (G41, G42) are reversed.
Note: When milling a shape with XY motions, turning on Mirror Image for
just one of the X or Y axes will change climb milling to conventional milling
and/or conventional milling to climb milling. As a result, the type of cut or
nish may not be what was desired. Mirror imaging of both X and Y will
eliminate this problem.
.
X0, Y0
Original
Mirror X
G101 Enable Mirror Image
X
Z
Y
Mirror Image and Pocket Milling
Program Code for Mirror Imaging in the X-Axis:
Program Example Description
%
O3600 (Mirror image X axis)
T1 M06 (Tool #1 is a 0.250” diameter endmill)
G00 G90 G54 X-.4653 Y.052 S5000 M03
G43 H01 Z.1 M08
G01 Z-.25 F5.
M98 P3601 F20.
G00 Z.1
G101 X0.
X-.4653 Y.052