Siemens SINUMERIK 802D sl Programming Manual

Enhanced Level Commands
4.1 Program support functions (1)
04.07
4-129
© Siemens AG 2007 All rights reserved
SINUMERIK 802D sl/840D/840D sl/840Di/840Di sl/810D ISO Milling (PGM) -- 04.07 Edition
Offset value +200.0 is set in offset No.11, +190.0 is set in offset No.15, and +150.0
is set in offset No.30
Program example
;
N001 G49 ; Tool length offset cancel
N002 G10 L10 P11 R200. ; Set tool offset 11 to +200.
N003 G10 L10 P15 R190. ; Set tool offset 15 to +190.
N004 G10 L10 P30 R150. ; Set tool offset 30 to +150.
N005 G92 X0 Y0 Z0 ;
;
Coordinate setting at reference
position
N006 G90 G00 Z250.0 T11 M6 ; Tool change
N007 G43 Z0 H11; ; Initial level, tool length offset
N008 S30 M3 ; Spindle start
N009 g99 G81 X400.0 Y-350.0
Z-153.0 R-97.0 F1200;
; Positioning, then #1 drilling
N010 Y-550.0 ;
;
Positioning, then #2 drilling and
point R level return
N011 G98 Y-750.0 ;
;
Positioning, then #3 drilling and
initial level return
N012 G99 X1200.0 ;
;
Positioning, then #4 drilling and
point R level return
N013 Y-550.0 ;
;
Positioning, then #5 drilling and
point R level return
N014 G98 Y-350.0 ;
;
Positioning, then #6 drilling and
initial level return
N015 G00 X0 Y0 M5 ;
;
Reference position return,
spindle stop
N016 G49 Z250.0 T15 M6 ;
;
Tool length offset cancel, tool
change
N017 G43 Z0 H15 ; Initial level, tool length offset
N018 S20 M3 ; Spindle start
N019 G99 G82 X550.0 Y-450.0
Z-130.0 R-97.0 P300 F700
;
;
Positioning, then #7 drilling,
point R level return
N020 G98 Y-650.0 ;
;
Positioning, then #8 drilling,
initial level return
N021 G99 X1050.0 ;
;
Positioning, then #9 drilling,
point R level return
N022 G98 Y-450.0 ;
;
Positioning, then #10 drilling,
initial level return

Siemens SINUMERIK 802D sl Specifications

General

Brand	Siemens
Model	SINUMERIK 802D sl
Category	Controller
Language	English