Example
Program code Comment
; Definition of tool D1:
$TC_DP1[1,1]=120 ; Type (end mill)
$TC_DP3[1,1]=20 ; Length compensation vector
$TC_DP6[1,1]=8 ; Radius
N10 X0 Y0 Z0 T1 D1 F12000 ; Selection of the tool.
N20 TRAORI(1) ; Activation of the transformation.
N30 G42 ORIC ISD=10 CUT3DC G64 X30 ; Activation of the 3D circumferential milling,
; continuous orientation changes at outside corners,
; insertion depth: 10 mm
N40 ORIWKS A30 B15 ; Orientation change at a corner through specification of axis po-
sitions.
N50 Y20 A3=1 C3=1 ; Traversing block with orientation change,
; specification of the orientation with direction vector.
N60 X50 Y30 ; Traversing block with constant orientation.
N70 Y50 A3=0.5 B3=1 C3=5 ; Traversing block with orientation change.
N80 M63 ; Block without traversing information.
N90 X0 ISD=20 ; Traversing block with change of the insertion depth.
N100 G40 Y0 ; Deactivation of the tool radius compensation.
N110 M30
Further information
Path and orientation
The type of circumferential milling used here is implemented by defining a path (guide line) and
the associated orientation. In this type of machining, the shape of the tool on the path is not
relevant. Only the radius at the tool intervention point is decisive.
Work preparation
3.13 Tool offsets
NC programming
756 Programming Manual, 12/2019, 6FC5398-2EP40-0BA0
To Next Page
Loading...
Need help?
General
