·220·
Programming manual
CNC 8055
CNC 8055i
10.
MULTIPLE MACHINING
·M· & ·EN· MODELS
SOFT: V02.2X
G65: Machining programmed with an arc-chord
10.6 G65: Machining programmed with an arc-chord
This function allows activated machining to be performed at a point programmed by means of an
arc chord. Only one machining operation will be performed, its programming format being:
[ X±5.5 ] Distance from the first machining point to the center along the abscissa axis
Defines the distance from the starting point to the center along the abscissa axis.
[ Y±5.5 ] Distance from the first machining point to the center along the ordinate axis
Defines the distance from the starting point to the center along the ordinate axis.
With parameters X and Y the center of the circle is defined in the same way that I and J do this in
circular interpolations (G02, G03).
[ A±5.5 ] Angle of the chord
Defines the angle formed by the perpendicular bisector of the chord with the abscissa axis and is
expressed in degrees.
[ I±5.5 ] Angular pass between machining operations
Defines the chord length. When moving from point to point in G00 or G01, the sign indicates the
direction, "+" counterclockwise, "-" clockwise.
[ C0/1/2/3 ] Type of move from point to point
Indicates how movement is made between machining points. If not programmed, a value of C=0
is assumed.
C=0: Movement is made in rapid feedrate (G00).
C=1: Movement is made in linear interpolation (G01).
C=2: Movement is made in clockwise circular interpolation (G02)
C=3: Movement is made in counterclockwise circular interpolation (G03)
[ F5.5 ] Feedrate to move from point to point
Defines the feedrate that is used for moving from point to point. Obviously, it will only apply for "C"
values other than zero. If it is not programmed, the value F0 will be taken, maximum feedrate selected
by the "MAXFEED" axis machine parameter.
G65 X Y A
I
C F
To Next Page
Loading...
