Siemens SINUMERIK 808D ADVANCED - Contour Milling - CYCLE72

Programming and Operating Manual (Milling)
6FC5398-4DP10-0BA1, 01/2014
167
Parameter
Description
Value
_WID Rectangle dimensions Y = +40 mm
_STA Angle of rotation in the plane 10 degrees
_MID Maximum infeed depth 6 mm
_MIDA Maximum infeed width 10 mm
_FDP Retraction at the end of the milling path 5 mm
_FALD Finishing allowance in depth No finishing allowance
_FFP1 Feedrate in the plane 4000 mm/min
_VARI Machining type 31 (Roughing parallel to the X axis with
alternating direction)
_FDP1 Overrun on last cut as determined by the cutting
edge geometry
2 mm
A milling cutter with 10 mm radius is used.
N10 T2 D2
N20 G17 G0 G90 G54 G94 F2000 X0 Y0 Z20
; Approach start position
N30 CYCLE71(10, 0, 2, -11, 100, 100, 60, 40, 10, 6, 10, 5,
0, 4000, 31, 2)
; Cycle call
N40 G0 G90 X0 Y0
N50 M02
; End of program
9.6.3
Contour milling - CYCLE72
Programming
CYCLE72 (_KNAME, _RTP, _RFP, _SDIS, _DP, _MID, _FAL, _FALD, _FFP1, _FFD, _VARI, _RL, _AS1, _LP1, _FF3, _AS2,
_LP2)
Parameters
Parameter
Data type
Description
_KNAME STRING Name of contour subroutine
_RTP REAL Retraction plane (absolute)
_RFP REAL Reference plane (absolute)
_SDIS REAL Safety clearance (to be added to the reference plane; enter without sign)
_DP REAL Depth (absolute)
_MID REAL Maximum infeed depth (incremental; enter without sign)
_FAL REAL Finishing allowance at the edge contour (enter without sign)
_FALD REAL Finishing allowance at the base (incremental, enter without sign)
_FFP1 REAL Feedrate for surface machining
_FFD REAL Feedrate for depth infeed (enter without sign)