Fagor CNC8 070 - 2000 Tool Radius Greater than the Arc Radius; 2001 Profile Damaged by Tool Radius Compensation; 2002 The First Block of the Linear Compensation Must be Linear; Errors 2000-2999

CNC8070
R
EF
. 0402
E
RROR SOLUTIONS
Page 79 of 128
Errors 2000-2999
ERRORS 2000-2999
2000 'Tool radius greater than the arc radius'
DETECTION During execution.
CAUSE The tool radius is greater than the radius of the arc to be machined.
SOLUTION Use a tool with a smaller radius.
2001 'Profile damaged by tool radius compensation'
DETECTION During execution.
CAUSE The tool radius is too large for the profile to be machined and, consequently, would
damage the profile.
SOLUTION Use a tool with a smaller radius.
2002 'The first block of the linear compensation must be linear'
DETECTION During execution.
CAUSE After activating tool radius compensation (G41 or G42), the next motion block is a
circular block. Tool radius compensation cannot begin in a circular block.
SOLUTION Tool radius compensation must begin in a linear block. Therefore, the motion block
that goes after G41-G42 must be a linear motion block.
2003 'Tool radius too large in consecutive arcs'
DETECTION During execution.
CAUSE When machining two consecutive arcs that make up a loop (intersect each other) The
tool radius is too large for machining the inside of the loop.
SOLUTION Use a tool with a smaller radius.
2004 'Too many motionless blocks between blocks that have tool radius
compensation'
DETECTION During execution.
CAUSE While tool radius compensation is active, too many motionless blocks (parameter
assignments P, variables, etc.) have been programmed between motion blocks.
SOLUTION Reduce the number of motionless blocks programmed. To do this, several of these
blocks may be combined into a single block.
2005 'The last block of the linear compensation must be linear'
DETECTION During execution.
CAUSE After canceling tool radius compensation (G40), the next motion block is a circular
block. Tool radius compensation cannot end in a circular block.
SOLUTION Tool radius compensation must end in a linear block. Therefore, the motion block that
goes after G40 must be a linear motion block.
2006 'Tool radius compensation (G41/G42) must be changed on a linear path'
DETECTION During execution.
CAUSE The tool radius compensation has been changed and the next motion block is a
circular block. In other words, G42 has been programmed while G41is active or vice
versa. The tool radius compensation cannot be changed if the next motion block is
an arc.
SOLUTION Program a linear motion block after (G41-G42).