HEIDENHAIN CNC PILOT 640 - Circular Arc of Turning Contour G12-;G13-Geo

DIN/ISO programming | Basic elements of turning contour
4
HEIDENHAIN | User's Manual smart.Turn and DIN Programming | 12/2017
251
Circular arc of turning contour G12-/G13-Geo
G12 and G13 define a circular arc in a contour with absolute center
dimensioning.
Direction of rotation:
G12: In clockwise direction
G13: In counterclockwise direction
Parameters:
X: Final point (diameter value)
Z: Final point
I: Center absolute (radius dimension)
K: Center absolute
R: Radius
Q: Intersect. pt. or Final point if the line segment intersects a
circular arc (default: 0)
0: Near point of intersection
1: Far point of intersection
BR: Chamf./round. – defines the transition to the next contour
element
When entering a Chamf./round., program the theoretical end
point.
No entry: Tangential transition
BR = 0: No tangential transition
BR > 0: Rounding radius
BR < 0: Width of chamfer
PZ: Final point (polar radius; reference: workpiece datum)
W: Final point (polar angle; reference: workpiece datum)
PM: Center (polar radius; reference: workpiece datum)
WM: Center (polar angle; reference: workpiece datum)
AR: Start angle – tangential angle to rotary axis
AN: Final angle – tangential angle to rotary axis
FP: Do not machine the element (only necessary for
TURN PLUS)
1: Basic element (line) do not machine
2: Overlay element (chamfer or rounding arc) do not
machine
3: Basic/overlay element do not machine
BE, BF, BD, BP and BH.
Further information: "Machining attributes for form elements",
Page 246
Programming:
X, Z: Absolute, incremental, modal or ?
ARi: Angle to the previous element
ANi: Angle to the subsequent element