HEIDENHAIN CNC PILOT 640 - 4.29 Other G Codes; Blank Contour G67 (for Graphics); Clamping G65; Period of Dwell G4

DIN/ISO programming | Other G codes
4
HEIDENHAIN | User's Manual smart.Turn and DIN Programming | 12/2017
439
4.29 Other G codes
Clamping G65
G65 displays the selected chucking equipment in the simulation
graphics.
Parameters:
H: No. of clamping – always H = 0
D: Fixture – no input
X: Start point – diameter of workpiece blank
Z: Start point (default: no input)
Q: Chuck form
5: Outside chucking
5: Inside chucking
B: Clamping length (B + P = length of blank)
P: Free length
V: Delete chucking equipment
Blank contour G67 (for graphics)
G67 displays an Aux. workpiece blank in the Simulation submode.
Parameters:
ID: Workpc. blank contour – name of the auxiliary workpiece
blank
NS: Starting block no. of contour – beginning of contour section
Period of dwell G4
With G4, the control interrupts the program run for the Period of
dwell F or the execution of revolutions on the recess floor D before
executing the next NC block. If G4 is programmed together with a
path of traverse in the same block, the Period of dwell or Number
of revolutions only becomes effective after the path of traverse has
been executed.
Parameters:
F: Delay in seconds (range: 0 < F <= 999)
D: Rev. on recessing floor
Precision stop ON G7
G7 switches Precision stop on. It is a modal function. With a
Precision stop, the control does not run the following block until the
last point has been reached in the tolerance window for position. The
tolerance window is defined in the posTolerance machine parameter
(no. 401101). Precision stop affects single paths and cycles. The NC
block containing G7 is also executed with a precision stop.