HEIDENHAIN CNC PILOT 640 - 4.10 Linear and Circular Movements; Linear Movement G1

DIN/ISO programming | Linear and circular movements
4
HEIDENHAIN | User's Manual smart.Turn and DIN Programming | 12/2017
293
4.10 Linear and circular movements
Linear movement G1
G1 moves the tool on a linear path at the feed rate to the end point.
Parameters:
X: Diameter
Z: Target point
AN: Angle
Q: Intersect. pt. or Final point if the line segment intersects a
circular arc (default: 0)
0: Near point of intersection
1: Far point of intersection
BR: Chamf./round. – defines the transition to the next contour
element
When entering a Chamf./round., program the theoretical end
point.
No entry: Tangential transition
BR = 0: No tangential transition
BR > 0: Rounding radius
BR < 0: Width of chamfer
BE: Special feed rate factor for Chamf./round. (default: 1)
Special feed rate = active feed rate * BE (range: 0 < BE <= 1)
Programming:
X and Z absolute, incremental or modal
If more axes are available on your machine, additional
input parameters will be displayed, e.g. parameter B for
the B axis.