HEIDENHAIN CNC PILOT 640 - Linear Slot, Lat. Surface G792

DIN/ISO programming | Milling cycles
4
HEIDENHAIN | User's Manual smart.Turn and DIN Programming | 12/2017
407
Linear slot, lat. surface G792
G792 mills a slot from the current tool position to the Final point.
The slot width equals the diameter of the milling cutter. Oversizes are
not taken into account.
Parameters:
Z: Final point
C: End angle
K: Length
A: Angle – rotation angle
XE: Milling floor
XS: Upper edge of milling
J: Milling depth
J > 0: Infeed direction –X
J < 0: Infeed direction +X
P: Max. approach (default: Milling in one infeed)
F: Approach feed for plunging (default: active feed rate)
Parameter combinations for definition of the end point: see help
graphic
Parameter combinations for definition of the milling plane:
Milling floor XE, Millg. top edge XS
Milling floor XE, Milling depth J
Millg. top edge XS, Milling depth J
Milling floor XE
Rotate the spindle to the desired angle position before
calling G792
If you use a spindle positioning device (no C axis), a
radial slot is machined parallel to the Z axis.
If J or XS is defined, the tool approaches to safety
clearance in X and then mills the slot. If J and XS are
not defined, the milling cycle starts from the current
tool position
Example: G792
%792.nc
N1 T8 G197 S1200 G195 F0.2 M104
N2 M14
N3 G110 C0
N4 G0 X110 Z5
N5 G0 X102 Z-30
N6 G792 K25 A45 XE97 J3 P2 F0.15
N7 M15
END