HEIDENHAIN CNC PILOT 640 - One-Sided Synchronization G62

DIN/ISO programming | Assignment, synchronization, workpiece transfer
4
HEIDENHAIN | User's Manual smart.Turn and DIN Programming | 12/2017
491
One-sided synchronization G62
Refer to your machine manual.
This function is only available on a machine with multiple
channels (option 153).
G62 enables you to program the synchronization of two slides. The
slide programmed with G62 waits until slide Q has reached the
synchronizing mark H that has been set with G162.
If you use parameter O for programming G62, the slide waits until
the synchronizing mark H and the programmed coordinate have
been reached.
Parameters:
H: Sync.mark no. – number of the synchronizing mark (range:
0 <= H <=15)
Q: No. of slide – slide for which the control will wait
O: Direction (default: 0)
O = –1: The slide waits until slide Q has traversed the
synchronizing mark in negative direction in the specified axis
direction.
O = 0: The slide waits until slide Q has reached the
synchronizing mark.
O = 1: The slide waits until slide Q has traversed the
synchronizing mark in positive direction in the specified axis
direction.
X: Diameter – coordinate at which the waiting process ends
Z: Length – coordinate at which the waiting process ends
Y: Length – coordinate at which the waiting process ends
Please note:
G162 and G62 must be defined in the same main
program.
If you are using coordinates, the control must reach
this coordinate. Therefore, instead of synchronizing
to the end point of an NC block, synchronize to a
coordinate that will reliably be traversed.
Example: G60
. . .
$1 N10 G62 Q2 H5
Slide $1 waits until slide $2 has reached the mark 5
...
$2 N40 G62 Q1 O1 H7 X200
Slide $2 waits until slide $1 has reached the mark 7, and
position X > 200
. . .