Tormach 1500MX - About Drilling and Tapping; Create a Drilling Sequence; Drilling and Tapping in Pathpilot

7: PATHPILOT TOOLS AND FEATURES
l To clear all values in the table, select Clear All.
l To make sure that the value is a valid number, leave the
cell. If the value isn't a valid number, it's erased, and an
error displays on the Status tab.
l Before posting the file, make sure that there are none of
the following:
o
X values without a Y value
o
Y values without an X value
o
An empty row before the last row with values
About Drilling and Tapping
A drilling and tapping program is used to create a series of
holes in defined locations on a part.
Drilling and Tapping in PathPilot
PathPilot has the following options to define the locations:
l
Pattern Use X and Y locations to make a list of hole
locations.
l
Circular Use a circumference to make a specific pattern
of evenly spaced holes.
For information on using conversational programming in
PathPilot to drill and tap holes, see "Create Hole Locations on a
Part (Drill/Tap)" (on the previous page).
During a drilling routine, PathPilot uses one of the following
canned G-code cycles, depending on the entries in each DRO
field:
l
G81 Drill
l
G82 Drill with dwell
l
G83 Drill with peck
Note: The features can't be combined, because
peck cancels dwell.
When using a tapping routine, PathPilot uses the G84 canned
G-code cycle. G84 is similar to G81, but it commands a spindle
reverse once it gets to the bottom of the hole.
It's important that the Z Feedrate matches the spindle RPM
and tap pitch, so the rate is calculated from the Pitch and RPM
DRO entries. The result is displayed in the Z Feedrate DRO (in
the left panel) after the Enterkey is selected in one of the
RPM, Pitch, or TPU DRO fields.
Note: An auto-reversing tapping head typically uses a
drilling cycle.
Create a Drilling Sequence
The Drill tab uses one of the following canned G8x cycles to
drill a hole at each identified location:
l
G81 Drill
l
G82 Drill with dwell
l
G83 Drill with peck
Note: The features can't be combined, because
peck cancels dwell.
Hole depth is usually defined as the full diameter portion of
the hole, so you may need to consider the Z length from the
drill point to the corner.
1. In the Spot Tool #DROfield, type the number of the spot
drill.
If a valid tool number is used in the Spot Tool
#DROfield, PathPilot makes a spot drilling sequence
before the drilling sequence. In the spot drilling
sequence, PathPilot uses the values indicated in the
Feedrate DROfield, the Spindle RPM DROfield, and the
ZClear DROfield.
Note: To skip a spot drilling sequence, leave the
Spot Tool # DROfield blank.
2. In the Spot Tool DOCDROfield, type the depth of cut for
the spot drilling sequence.
Note: To skip a spot drilling sequence, leave the
Spot Tool DOCDRO field blank.
3. In the Peck DRO field, type the distance for each peck.
Note: Any entry greater than 0 typed in the
Peck DROfield replaces G81 with G83 in the G-
code. For information, see "Drilling and Tapping
Reference" (on the next page).
4. Set the parameters for the hole in the Z range:
a. In the ZStart DROfield, type the location for the first
Z pass.
b. In the ZEnd DROfield, type the location for the last
Zpass.
©Tormach® 2024
Specifications subject to change without notice.
Page 129 UM10811: 1500MX Operator's Manual (Version 0424A)
For the most recent version, see tormach.com/support