HEIDENHAIN TNC 620 Programming Station

Subprograms and program section repeats | Programming examples
Example: Groups of holes
Program run:
Approach the groups of holes in the main program
Call the group of holes (subprogram 1) in the main
program
Program the group of holes only once in
subprogram1
0 BEGIN PGM UP1 MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL CALL 1 Z S5000
Tool call
4 L Z+250 R0 FMAX
Retract the tool
5 CYCL DEF 200 DRILLING
Cycle definition: Drilling
Q200=2 ;SET-UP CLEARANCE
Q201=-10 ;DEPTH
Q206=250 ;FEED RATE FOR PLNGNG
Q202=5 ;PLUNGING DEPTH
Q210=0 ;DWELL TIME AT TOP
Q203=+0 ;SURFACE COORDINATE
Q204=10 ;2ND SET-UP CLEARANCE
Q211=0.25 ;DWELL TIME AT DEPTH
Q395=0 ;DEPTH REFERENCE
6 L X+15 Y+10 R0 FMAX M3
Move to starting point for group 1
7 CALL LBL 1
Call the subprogram for the group
8 L X+45 Y+60 R0 FMAX
Move to starting point for group 2
9 CALL LBL 1
Call the subprogram for the group
10 L X+75 Y+10 R0 FMAX
Move to starting point for group 3
11 CALL LBL 1
Call the subprogram for the group
12 L Z+250 R0 FMAX M2
End of main program
13 LBL 1
Beginning of subprogram 1: Group of holes
14 CYCL CALL
Hole 1
15 L IX+20 R0 FMAX M99
Move to 2nd hole, call cycle
16 L IY+20 R0 FMAX M99
Move to 3rd hole, call cycle
17 L IX-20 R0 FMAX M99
Move to 4th hole, call cycle
18 LBL 0
End of subprogram 1
19 END PGM UP1 MM
8
HEIDENHAIN | TNC620 | Klartext Programming User's Manual | 01/2022
263